Drawing view styles control the appearance of:
Different types of drawing views. These include principal views, 2D Model views, section views, auxiliary views, and detail views.
Different types of view annotations. These include cutting planes, viewing planes, and detail envelopes.
Drawing view caption content and formatting.
To understand the overall process for defining drawing view captions, view annotation captions, and view annotation labels, refer to the Drawing view style workflow.
You can use Drawing View styles to customize the appearance of drawing views and view annotations.
Example:
Within a single overall style, such as ISO, ESKD, or GB, you can define unique content and formatting for each drawing view type and for each view annotation.
You can create a new drawing view style for a specific customer or supplier, such as Customer ABC or Supplier XYZ, and use the style to customize the appearance of different drawing view types and view annotations to meet their requirements.
While the recommended way to use drawing view styles is to create a single style for a specific business or industry, it is possible to define a different drawing view style for different drawing view types. For example, you can create a style to apply to section views and to the cutting planes used to define them, and name the new style Section.
You can apply formatting to drawing views, view annotations, and caption text by doing any of the following:
Use the Styles command to create and name a new drawing view style, or to modify an existing drawing view style. Independent primary and secondary caption text and formatting can be defined for each drawing view type in the Drawing View Styles dialog box.
Ensure the drawing view style is used consistently. You can map a drawing view style to each type of drawing view using the Drawing View Style tab (Solid Edge Options dialog box).
To learn how, see Map drawing view styles.
Modify the properties of a single, selected drawing view or view annotation. For example, you can use the Caption tab (Drawing View Properties dialog box to modify the default drawing view caption or view annotation caption defined in the drawing view style.
Using the Styles command to create and modify drawing view styles
Whether you are creating or modifying a drawing view style, you begin with the Styles command and the Style dialog box, where you set the Style Type to Drawing View. You can select the New button to create a new style or the Modify button to change an existing style.
The Drawing View style identifies the name of the style and defines:
The display properties of different types of drawing views.
The default content and formatting of drawing view captions.
The appearance of the lines used by cutting planes, view planes, and detail view envelopes.
The Drawing View Style dialog box contains four tabs:
Use the Name tab to name a new drawing view style that you are creating. If you are modifying a style, you can select a different style or no style as the basis for your changes.
Use the Lines tab to specify the appearance of lines and terminators used in cutting planes, view planes, and detail envelopes, and in the section, auxiliary, and detail drawing views that are derived from them.
Use the Caption tab to specify the property text-derived content of the primary caption and the secondary caption for each type of drawing view and view annotation. This is also where you control whether a caption is shown or not shown by default when a drawing view or view annotation is placed on the drawing.
Use the Caption Format tab to specify the formatting of the caption and its location with respect to the drawing view or view annotation.
To learn the basic procedure for creating drawing view styles, see the Help topic, Create or modify a drawing view style.